Continue to Site

Welcome to EDAboard.com

Welcome to our site! EDAboard.com is an international Electronics Discussion Forum focused on EDA software, circuits, schematics, books, theory, papers, asic, pld, 8051, DSP, Network, RF, Analog Design, PCB, Service Manuals... and a whole lot more! To participate you need to register. Registration is free. Click here to register now.

Register Log in

How to do dc sweep 2 variables input in cadence spectre

Status
Not open for further replies.
T

tompham

Full Member level 2
Full Member level 2
Joined
May 29, 2010
Messages
133
Helped
29
Reputation
60
Reaction score
29
Trophy points
1,308
Location
usa
Visit site
Activity points
2,066
Hi all

Anyone know how to run cadence spectre with sweeping 2 input variables? Let say sweep vgs and vds of nmos

Thank your
 

Use nested sweep analysis.
Code: 
swp_vds sweep param=vds start=0 stop=1.5 step=0.1 {
    swp_vgs sweep param=vgs start=0 stop=0.5 step=0.1 {
         .......
    }
}

See result "spectre -h sweep".
 
Last edited:

Hi pancho_hideboo

Where I can add the lines you mention? In input.scs? and after adding the lines I need to run not to netlist and run?

Thanks
 

Cadence Spectre have multiple sweep analyses using sweep analysis.
See "spectre -h dc" and "spectre -h sweep".

If you run Spectre simulation from Unix Command line such as "spectre input.scs".
You can use following analysis statement.
Code: 
swp_vds sweep param=vds start=0 stop=1.5 step=0.1 {
    swp_vgs dc param=vgs start=0 stop=0.5 step=0.1 {
         .......
    }
}

However it can not be available directly, if you run Spectre from Cadence ADE.
You can specify vgs sweep as dc native sweep from ADE.
However you can not set sweep analysis for vds from ADE.

Instead you can use Parametric Analysis for vds sweep.
This is ADE function not Spectre function.
ADE's Ocean generates input.scs with changing vds.
This is equivalent to the following.
Code: 
spectre input_vds1.scs
spectre input_vds2.scs
   ....
   ....
spectre input_vds_N.scs

You can not use full ability of Spectre if you run it from ADE.
 
Last edited:
Hello
pancho_hideboo Wrote:
You can not use full ability of Spectre if you run it from ADE.
Click to expand...
Is there quick start guide documents to learn full ability of spectre?
tnx
 

Hello pancho
I googled for
Virtuoso Spectre Circuit Simulator and Accelerated Parallel Simulator User Guide
Click to expand...
, and I found:
Spectre Circuit Simulator User Guide
which have 334 pages. Is it what you have mentioned?
 

Every time I had to do nested loops, I used the Parametric
Analysis tool and a DC OP. You may not find any value in
a continuous sweep. You -could- run Spectre native or
under Ocean, but if you are in the graphical environment
maybe you'd rather get to the outcome and skip the voyage
of discovery. Unless said voyage is the point of it all.
 

Status
Not open for further replies.

Similar threads

Part and Inventory Search

Welcome to EDABoard.com

Sponsor

Back
Top